Jump to content
Rahul Ponginan

Linear Buckling Analysis

Recommended Posts

Hello,
We are new to that topic and want to make a linear buckling analysis, but we don’t know, how to interpret the results in hyperview. Is it critical, when the magnitude of the buckling mode is higher than one? How can we figure out the safety factor?
What does the number at “Mode 1 – F = 2.519563E+00” or “Mode 2 – F = 2.655379E+00” in the dropdown on the left mean?
Thank you for your help

Share this post


Link to post
Share on other sites

Hello,


the number of the mode can be interpreted as a safety factor vs. buckling. So a value of 2.5 means, that 2.5 times the applied load will lead to buckling failure. You can look up "Linear Buckling Analysis" in the OptiStruct help for a more detailed explanation.


Jan


Share this post


Link to post
Share on other sites
Guest

Hi NarasimhaMurthy,


 


You can use RADIOSS (Block) to solve Non linear buckling problems.


 


Please refer to RADIOSS Example 38 - Buckling of L-Shaped Beam


Share this post


Link to post
Share on other sites

Is it possible in OptiStruct to run a linear buckling analysis and to apply selected buckling modes with a scaling factor as initial deformation or imperfection for a non-linear analysis like in Abaqus?

Share this post


Link to post
Share on other sites

Hi,

 

While nonlinear buckling could be done in Optistruct, it is very is likely the implicit solver will experience convergence difficulties resulting in long run times or even fail due to nonconvergence. Alternatively use Radioss integration to solve your model with the explicit method in Optistruct.

 

Therefore I suggest using Radioss explicit solver instead following this procedure:
1.perform modal analysis in Optistruct
2.in postprocessing create a derived load case>linear superposition>use small scale factor (1e-2 to 1e-3)

3.export the deformed shaped.

4. import the deformed shape into Hypermesh Radioss user profile and set up non-linear buckling analysis.

 

By using the deformed shape obtained from the modal analysis the structure will have geometry imperfection triggering a buckling pattern consistent with modal and linear buckling analysis.

 

Nonlinear buckling analysis is recommended to be performed within Radioss. Post buckling can be solved using nonlinear geometry (Implicit) loadcase. Use any of the Arc-Length methods to solve post-buckling analysis.

Buckling.pdf1.46 MB · 130 downloads

2_2_snap_roof___implicit.pdf663.71 kB · 105 downloads

 

There are two tutorials and one example on NL buckling: 

  • RD-T: 3030 Buckling of a Tube Using Half Tube Mesh (Hypercrash)
  • RD-T: 3530 Buckling of a Tube Using Half Tube Mesh (Hypermesh)
  • RD-E: 0300 S-Beam Crash

RD-T_ 3030 Buckling of a Tube Using Half Tube Mesh.pdfUnavailable RD-T_ 3530 Buckling of a Tube Using Half Tube Mesh.pdfUnavailable RD-E_ 0300 S-Beam Crash.pdfUnavailable

Brian DO likes this

Share this post


Link to post
Share on other sites
On 5/16/2020 at 2:50 AM, Simon Križnik said:

Hi,

 

While nonlinear buckling could be done in Optistruct, it is very is likely the implicit solver will experience convergence difficulties resulting in long run times or even fail due to nonconvergence. Alternatively use Radioss integration to solve your model with the explicit method in Optistruct.

 

Therefore I suggest using Radioss explicit solver instead following this procedure:
1.perform modal analysis in Optistruct
2.in postprocessing create a derived load case>linear superposition>use small scale factor (1e-2 to 1e-3)

3.export the deformed shaped.

4. import the deformed shape into Hypermesh Radioss user profile and set up non-linear buckling analysis.

 

By using the deformed shape obtained from the modal analysis the structure will have geometry imperfection triggering a buckling pattern consistent with modal and linear buckling analysis.

 

Nonlinear buckling analysis is recommended to be performed within Radioss. Post buckling can be solved using nonlinear geometry (Implicit) loadcase. Use any of the Arc-Length methods to solve post-buckling analysis.

Buckling.pdf1.46 MB · 130 downloads

2_2_snap_roof___implicit.pdf663.71 kB · 105 downloads

 

There are two tutorials and one example on NL buckling: 

  • RD-T: 3030 Buckling of a Tube Using Half Tube Mesh (Hypercrash)
  • RD-T: 3530 Buckling of a Tube Using Half Tube Mesh (Hypermesh)
  • RD-E: 0300 S-Beam Crash

RD-T_ 3030 Buckling of a Tube Using Half Tube Mesh.pdfUnavailable RD-T_ 3530 Buckling of a Tube Using Half Tube Mesh.pdfUnavailable RD-E_ 0300 S-Beam Crash.pdfUnavailable

Thanks  Simon Križnik

 

I will do it with your guide.

Share this post


Link to post
Share on other sites

just highlighting a couple enhancements on this, extracted from RElease notes.

OS 2019.0 brought RIKS method for helping these unstable snap-trhu behavior.

 

OS 2019.1

Imperfection
An imperfection can be applied to the model.
Note: Only supported for Nonlinear Analysis.
The IMPERF Bulk Data and Subcase Entries can be used to apply an imperfection. An imperfection can be introduced into the model in the following ways:
  • TYPE=H3DRES on IMPERF Bulk Data: An h3d file is referenced which contains previously completed analysis results.
  • TYPE=GRID on IMPERF Bulk Data: The perturbation of grids can be directly applied.

 

 

OS 2019.0

 

Snap-thru with Arc-Length method
The Arc-Length method has been implemented to solve snap-thru problems in nonlinear analysis. Solution control is available thru the NLPCI Bulk Entry and three methods (Crisfield, Riks, and Modified Riks).

 

Simon Križnik likes this

Share this post


Link to post
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
You are posting as a guest. If you have an account, please sign in.
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

  Only 75 emoji are allowed.

×   Your link has been automatically embedded.   Display as a link instead

×   Your previous content has been restored.   Clear editor

×   You cannot paste images directly. Upload or insert images from URL.


×
×
  • Create New...