Jump to content
priyankabhola

contact master slave in optistruct

Recommended Posts

Hi,

 

i am doing analysisin optistruct 

project detail as per following.

 

load body (load caring vehicles).

payload  37ton apx.

traget: i want to test strength for floor members . not only floor even all side walls of vehicles. can sastain the load.

 

problem: master --dummy weight in 3d mesh 37 ton. 2.) slave: load body mesh part. but master weight run out of load body .connect not work properly betwen body and dummny weight.weight goes out of side walls .please help.  i dont want to apply pressure or force because at a time it work either on floor or side wall of load body. i want dummy weight will work at a time all sides (floor side and front and rear wall)

file attached for ref.

 

With regards

priyanka

 

attachments.zip

Share this post


Link to post
Share on other sites
1 hour ago, priyankabhola said:

Hi,

 

i am doing analysisin optistruct 

project detail as per following.

 

load body (load caring vehicles).

payload  37ton apx.

traget: i want to test strength for floor members . not only floor even all side walls of vehicles. can sastain the load.

 

problem: master --dummy weight in 3d mesh 37 ton. 2.) slave: load body mesh part. but master weight run out of load body .connect not work properly betwen body and dummny weight.weight goes out of side walls .please help.  i dont want to apply pressure or force because at a time it work either on floor or side wall of load body. i want dummy weight will work at a time all sides (floor side and front and rear wall)

file attached for ref.

 

With regards

priyanka

 

attachments.zip 34.02 MB · 0 downloads

 

 

Hi, 

 

I opened your model. Your master ELSET is empty (there is 0 element) : 

image.png.f16a68755634784645213eb1dafcb176.png

 

I have a question for you : Why are you using Linear Static step ? Why not Non Linear Quasi-Static ?

 

Best regards, 

Share this post


Link to post
Share on other sites

Hello,

Thanks for your reply,

 

actually reason for using linear static is time save i just want to check the total stress on floor for optimization first .  

if it will behave ok and after that i want to go for non linear.

 

can you guide me or help for non linear for the same project.

 boundary condition or deck setup.

 

or share some tutorial.

 

with regards

priyanka

Share this post


Link to post
Share on other sites

Hi,

 

there are several issues in your model:

  • the payload is modeled with shell elements, but solid element would be more appropriate. The upper surface shell would sag under gravity and its weight would be transferred only by side shell surfaces. Solid elements would equally distribute the weight over the floor.
  • the "lc6" load collector referenced in linear static load step is empty, which is invalid (the solver will error out). Reference a gravity load collector "0.1_z negi" instead.
  • the master component is usually stiffer or in case of equal stiffness the one with the coarser mesh. In your case, the cargo has the same stiffness and mesh size as a steel cargo box, but I would still choose the cargo as a slave.
  • Sliding contact might not work using linear static analysis. In linear static analysis, the contact status does not change, does not slide and the contact stiffness is constant. Freeze Contact enforces zero relative motion on the contact surface, the contact gap opening remains fixed at the original value and the sliding distance is forced to be zero. Additionally, rotations at the slave node are matched to the rotations of the master patch. The FREEZE condition applies to all respective contact elements, regardless of whether they are open or closed. Freeze Contact can be activated using TYPE=FREEZE on the CONTACT, MU1=FREEZE on the PCONT entry or by using the Penalty-based Tied Contact. Penalty-based tied contact is activated by using the TIE entry for the contact interface (with CONTPRM,TIE,PENALTY, the default).

Share this post


Link to post
Share on other sites

Join the conversation

You can post now and register later. If you have an account, sign in now to post with your account.

Guest
You are posting as a guest. If you have an account, please sign in.
Reply to this topic...

×   Pasted as rich text.   Paste as plain text instead

  Only 75 emoji are allowed.

×   Your link has been automatically embedded.   Display as a link instead

×   Your previous content has been restored.   Clear editor

×   You cannot paste images directly. Upload or insert images from URL.


×
×
  • Create New...